I would like to use the Height property in Orcad Capture and transfer it to Allegro PCB Editor. I am able to get the height property exported from Orcad and attached as a property in Allegro as a componemt property.But I have not been able to get it to replae the Package_height_max property for DRC checking. If anyone has this working please let me know the steps required.
Below is an excerpt fro mthe props ref document. I know it is written for Concept but thisshould work for Orcad too.
HEIGHTThe HEIGHT property, attached to component definitions in a schematic system and a valuemaintained in user units in the database, controls package height and can be sourced fromthe Allegro Design Entry HDL Part Table File (PTF). For discrete parts, whose physicalfootprints are identical except for height variations due to multiple manufacturers, use the PTFpackage height model, which minimizes design disruption as front-end librarians may alreadybe using this property for IDF support.When creating the physical footprint, ensure that no PACKAGE_HEIGHT_MAX property isassigned to place-bound shapes. Only those symbols whose height is driven from theschematic require this change. (Any existing HEIGHT properties assigned to packagesymbols take precedence.)
Give this a try:-
2. Edit the allegro.cfg file to include Component_Height=HEIGHT under ComponentDefinitionProps.
For access this capability, you must be running 16.2 or newer.
Allegro has a order of precendence in dealing with the PACKAGE_HEIGHT_MAX or MIN properties
If you built your symbols (.dra) and assigned the PACKAGE_HEIGHT_MAX property to tjheir place bound shapes, this will always win over any HEIGHT (or PACKAGE_HEIGHT_MAX) properties injected from the schematic. So if you want to drive some or all of your place bound height values from the schematic part libraries, you should inspect your symbol files (.dra) for package height properties.