Has anybody tried to do SI analysis from HDL XL directly. When i exported the net to SI the topology gets extracted to SIGxp but the Results and Measurement does not appear in SIgxp. With out this i cannot simulate the toplogy.
> Now i am saving the same topolgy and then simulating the same by opening the Sigxp separately.Cant we simulate the topology directly?
> I wanted to know about the properties about the transmission line which is passing to SigXp. Will it take only the constraints set in CM only? In that case we can create the topology independent of schematic in SigXP directly...
It's possible that you are running Concept from an non SI license, in this case, you will be able to get SigXP to open and extract "stuff" but you won't be able to simulate it without the "simulator" license. In Concept, use File>Change Product to select an SI license and see if that dows the trick.
In reply to oldmouldy:
Do you have Allegro PCB SI installed on the same pc as Concept HDL XL? If yes, then the problem could be that the tool is invoking that version of SigXP that does not include analyze/measurement capabilities. Try this: close all Cadence tools > double click on System icon in control panel > in system variables section add the SIGXP_TIER variable with it's value set to SELECT. Now see if you can get the tool to give you the option to select the version of SigXP that comes with Allegro PCB SI. If yes, select that version and click OK.
In reply to Khurana:
One more tit bit about topologies that are extracted from Concept CM. Since Concept has no understanding of the board real estate all the tlines comes out as 2800 mils in length. You may define min/max propagation rules, length matching rules in SigXP and then "backannotate" them by clicking on the Update Constraint Manager icon OR save the topology file by giving it a name then import the topology file as an Electrical Constraint Set (ECSet) in Constraint Manager by going to File > Import > Electrical Constraint Set. Lastly, you may also assign models to parts in Concept schematic. This is done by going to Tools > Assign Models (if I am not mistaken). You may select the .dml and attach it to the symbol in schematic so that when the topology is extracted the corresponding buffer (model) is what you get in SigXP. Try out the Concept/CM tutorials on this in Help - they are very good.
Thnx khurana it worked after assigning in the env variables..
Oldmouldy: With SI suite it doesnot allow us to work the concept hdl..The suite should be be hdl l r hdl xl...
Anyways thnx for the suggestions.