Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
This course combines our Allegro PCB Editor Basic Techniques, followed by Allegro PCB Editor Intermediate Techniques.
Virtuoso Analog Design Environment Verifier 16.7
Learn learn to perform requirements-driven analog verification using the Virtuoso ADE Verifier tool.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
I just loaded a netlist into a board where the default grid is set to 0.025". None of the parts came in on this 25 mil grid.
What is the trick to getting them on grid? (I hope it is not manually as there are over 700 parts............)
Some more details:
I set up rooms and did a quick place by room. None of the parts have been placed on my 25 mil grid. If I go into placement edit mode and select a part, then go up to the tool bar and select Place>Manually, the part will snap to grid and I can then place it on grid.
How can I make this happen automatically?
(Running the latest update)
In reply to TH Designs:
Response from Cadence:
The Quickplace utility just throws the parts into the rooms
on the board in no particular placement order and does not place them on a
specified grid. With the move command selecting the parts individually will
place the part’s origin on grid. However, this is not the case if you move a
group of parts.
The software does not have a utilities that either places
them all or moves them all and automatically places them all on grid. The
software expects that as you determine the exact location you want to position
the part you will use the Place > manually command to select and place the
part or use the Edit > Move command to specify its move a part to the exact
Maybe you could consider using Auto Placement (Place > Autoplace) to place the components based on the auto-placement grid.
Here are the quick steps:
1) Setup > Areas > Package Keepin - Define shape where components can be placed, required by the next step.
2) Place > Top Grids - Enter the X and Y Grid increment and indicate the origin point of the grid lines. (This will add a hatch grid on Board Geometry / Place_Grid_Top used when auto placing components)
3) Edit > Property - Add the PLACE_TAG component property to all the parts you wish to auto place, could select them all.
4) Place > Autoplace > Design - This will place all the components with the PLACE_TAG property within the board outline on the placement grid defined in Step 2. (Note: Use Place > Autoplace > Parameters to change the component origin point; Body center, Symbol Origin or Pin 1) That's it. Play with it a little bit. Sort of a weird use of the functionality but it may give you what you need.
The one major difference compared to Quick Place is Auto Place places the components on the board using the hatch grid defined on Board Geometry / Place_Grid_Top and Place Grid_Bottom subclasses.
Hope this helps,Mike Catrambone
In reply to mcatramb91:
Thanks Mike. I just tried that on a smaller job I'm starting and it works well.
I have found that eventhough quick place does not put the parts on any specific grid, once I select each part for the detailed placement, they will snap to the specified grid.
No problem, I am glad I could help. In some cases I wish Quick Place would be driven by a grid as well, or at least have an option to snap to a grid.
You could also use Autoplace to place by room. If you already have a ROOM property on your components then you would need to define ROOM shapes using Setup > Areas > Room Outlines with a ROOM Name matching each of your different ROOM component properties. In this case you don't want to add a PLACE_TAG property to your components because its placement will be driven by the ROOM property attached to the components.
It is a little time consuming because you Auto place one ROOM at a time using Place > Autoplace > Room then select the ROOM for auto placement. If you have a lot of ROOMS to place you could generate a small script file to run Autoplace by Room (example shows Auto Placement of ROOM MEMORY and PROCESSOR)
place area room ; fillin "MEMORY" place area room ; fillin "PROCESSOR"
If you would like to see how you can place and organize parts in Allegro at least twice as fast, see this web site and scroll down to the place command. There is a pdf and video that explains how it works.
If you like what you see, then go ahead and request a FREE evaluation license.
"Better, Faster and Easier Allegro PCB Design!"
In reply to dalTools:
Oops, there was a typo in the web address. Sorry.
One more time, forgot an s.
Not to hijack the thread but wanted to add those tools for Allegro are so very very nice.
Very good work that