Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
This course combines our Allegro PCB Editor Basic Techniques, followed by Allegro PCB Editor Intermediate Techniques.
Virtuoso Analog Design Environment Verifier 16.7
Learn learn to perform requirements-driven analog verification using the Virtuoso ADE Verifier tool.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
Hello,Any easy way to replace a via in a design without the use of skill.Thanks,Mihai
Tools->Padstack->Replace, then put in the old and new padstack names. Can do for the entire board or just a single via. You can also record these steps in a script and assign it a keyboard shortcut.G'Day,R²
I tried the first suggestion and it worked.I have created a .scr per your suggestion, but when I run it the script replaces all the vias with the desired padstack.
On the script be sure to check "Macro record mode".When recording the script: after inputing the padstack names and before clicking on "Replace", check the box "Single via replace mode".
when I try to do that the Single via replace mode is grayed out.
That's different from the version of 15.5 I'm running. As soon as I enter the "Old" padstack name, that box isn't greyed out any more. That's why I said to select that box after entering your padstack names.
When I try to replace the padstack by clicking on via to grab the old pastack info the sigle via replace mode is not greyed out, but when I try to manually entering the old and new padstacks the single padstack replace is greyed out.The reason why I manually need to manually enter the padstacks is for the script to record padstacks instead of my x/y coordinates.Can you by any chance send me this script and I can try and see if it works.You can use any two padstacks and I will replace yours with mine.Thanks,Mihai
The reason the box stayed greyed out is because you didn't pick the old padstack in the board file instead of using the list. Try the following script. Replace "my_new_padstack" with your new padstack (note that the padstack name must be in quotes). When you run the script, the command window will say "Pick origin for macro". At this point you pick the center of the via you want to replace (your grid must be fine enough to accurately pick this via). The via will be replaced with the padstack name in the script file ("my_new_padstack" in my example). If you're doing multiple replacements, you may want to turn off On-Line DRC, then turn it back on when you're done.# Allegro script# start time: Tue Apr 11 17:09:25 2006# Version: 15.5 s047 (v15-5-81BV) i86version 15.5
setwindow pcbtrapsize 155# Macro file: coordinates are relative to pick on replay.replace padstack pick_originpick rel grid 0.00 0.00setwindow form.miniFORM mini newname_browse fillin "my_new_padstack"FORM mini viamode YES FORM mini replace setwindow pcbdone
# stop time: Tue Apr 11 17:09:55 2006
Randy,It worked.Thank you so much.Mihai
I think you can also use the group edit to replace the via in area.