Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
I have a board with a lot of RF connectors, and 5 different ground nets for different board sections. The footprint for the RF connector has 2 ground pads, and one signal pad, and also some static shapes connected to the ground pads that will make the signal pin coplanar waveguide. I have defined those shapes seperately because it needs to be a precise width, and the spacing is a precise amount that I don't want defined by the constraint manager.
For most of my board it recognizes these static shapes as belonging to the ground nets where it is physically connected to the connector ground pins, and thus it properly connects it to the ground pour that I have on the top layer. On some sections of my board, it is only showing up as belonging to the Dummy Net on Etch/Top, and thus the ground pour is not being fully connected to this static shape - it is using the shape-shape spacing rules to put a void in between. This is still the case when I have a ground via connecting this static shape to the ground plane beneath it.
I have tried re-netlisting the design,refreshing the symbol drawing, updating shapes to smooth, checking shape outlines in DB Doctor, derive connectivity, and save-exit-reopening, but it is staying as Dummy Net. I know that I could redraw the symbol drawing and create a pad which I draw to be this irregular shape. I would prefer not to do that since it takes quite a bit longer, and the static shapes have worked properly at least in some sections of my board - I just don't know why yet.
What do I do to get these static shapes to show up with the net of the pin that they are overlapping?
Sounds like you're doing it right so without seeing the board I don't know what's wrong.For the time being select the shape manually and assign the net. Should clear up.
I am assuming that the static shapes have been defined inside of the RF connector symbol. If this is the case then the only time that these static shapes will assume the net name of the pins that are connected to (flooded on top) is when they are placed in the design. If you copy the RF connector symbol around the board the static shapes will assume Dummy Net and will remain that until you manually reassign the static shape to GND. Doing a Netlist import or symbol refresh has not effect on these static shapes, as you found, because you only have one shot of automatically assigning these static shapes to the nets of the pins that are flooded on top of is when the are placed on the board.
My suggestion is to generate a placement file of the design using File > Export > Placement, deleted the RF Connectors with the Dummy Net static shapes and reload the placement file using File > Import > Placement. This will replace the RF Connectors and in doing this the static shapes will associate to the Pins they are flooded on top of in the connector symbol
Hope this helps,Mike CatramboneUTStarcom, Inc.
In reply to mcatramb91:
Thanks Mike, the trick with exporting and importing the placement worked!
It is interesting to note that all of these connectors were placed before I updated the part symbol to include this additional shape. However, some of them had the proper net, and some did not. Sometimes there were two shapes in the same part symbol, one which assumed the net, and one which didn't.
Also it is useful to note for others reading this thread that this import/export trick only worked for the connectors that had this static shape already connected to the appropriate ground net. It is not inheriting the net from the pin that it is connected to. In fact, by placing a shape with a different net altogether on top of the static shape that is in the part symbol, it will inhert that net rather than the net of the ground pad (with ground net) that it is also connected to.