Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
im using cadence allegro 16.5 version. and for some reason the tapered trace function wont work on a selected cline?
i have attached an image with this of the issue and you can see why i wish to taper. the function says it has finished but the cline stays the same.
i know that there is a desired angle and tapered trace options in the settings for tapered traces but im not sure how this works? would anyone know the optimal settings to get this to work?
all help is welcome.Thanks
Fran the tapered trace function works on two clines of different widths only. No DRC must exist on the net for it to work.
Try this as a test. Draw a trace with a width of 50 mil for about an inch in length then reduce the trace width down to say 25 mils and continue on routing for about an inch.
Go to the gloss menu "Route > Gloss > Fillet Parameters.
Check the option at the bottom of the window "Tapered Traces" I set a desired angle of 60 and a offset of 200, click ok to dismiss the dialog.
Go back to the route gloss menu and select add a tapered trace. in the find menu make sure cline is checked. Draw a box with your cursor around the point where the 50 mil trace intersects with the 25 mil trace and a little fillet will be put in to taper the trace.
Hope that helps,
Quick edit here, Fran in your picture I am not sure if that is a pin that the trace is connected to or not. If it is a pin then you dont need to use the tapered trace option. Just use a fillet instead. Come off the pin with a trace of a suitable size and then gloss it with a fillet.
In reply to ScottCad:
I am not very clear, maybe you can come here to have a look.
yes this is a pin. could you elaborate a bit on how to use the fillet function i have ever used it before. Thanks for the help.
In reply to FrancisFogarty:
i tried using the add fillet but it only trys to correct the point of entry between pad/pin and cline.
but the extra etch over the pad as indicated by the arrow is the problem. i need this to taper like the pad but it wont work and i dont know what my options are. thanks
I think perhaps the easiest thing to do is extend the pad "Shape" on that pin out further so you can route your trace to it. That would enable you to keep your existing trace width and keep the taper on the pad.
Would that work ?
thanks for the reply. i dont want to have to do that because this is an RF SMA launch footprint and is designed as specified by the manufacturers for this board stackup for optimal performace.
is there any way that i could change the origin of the Pin so that it doesnt snap to the center of the pin? inste4ad it would possibly connect around the leading edge?
Fran could you possibly attach the symbol for that footprint ?, I would be glad to take a look at it.
here are the files.
Hi Fran, I took a look at your symbol. I think the best way to route a trace to that Tapered center pad is to extend the pad edge out further. so when you route the trace to it you can preserve the taper. I tried a few things and that was the best I could come up with.
The issue is you more than likely have to use a trace that is a certain width but when you route the trace it is snapping to the center of the pin and because your trace is wider than the tapered pad at that point you get overlap.
To work around this Extend out the shape before it tapers. You can do this by just drawing another shape to the left of the wide edge of the pad keeping the width the same and then just merge both shapes into 1 shape. This will save you having to move your existing pad.
when you route your trace to the pad start with a small width to clear the taper then change the width to your required width and it should flow nicely. It will look like a nice tapered transmission line when done.