Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
This course combines our Allegro PCB Editor Basic Techniques, followed by Allegro PCB Editor Intermediate Techniques.
Virtuoso Analog Design Environment Verifier 16.7
Learn learn to perform requirements-driven analog verification using the Virtuoso ADE Verifier tool.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
In Allegro 15.2 I had this test thru via V30C16D.I would like to use this same via as a test point in 15.5.1 but I don't know how to set it up.Can someone help me with this?Thanks,Mihai
I have made this change.But when I try to go Testprep manual -> Add I get this message.E- Can't create probe: Pad Too Small
Check your "Min pad size" in the "General Parameters" tab.
I have changed the min pad size to 0.0 just like in 15.2.When I try to manually add a test point now it creates a test point, but does not replace the via with the right via that I assigned in the Tesprep Param->Padstack Selections.
At the bottom of the Padstack Selections tab, click on the "Load new existing vias" button. If you get multiple lines that you don't need, right-click on the line and select "Delete". Then check the "Replace vias" box, then enter the "BOTTOM Side Replacement", then check the "Enable" box.
Your suggestions worked up till "Enable".It will not let me enable the new via, and every time I get to the padstack selection window the bottom window is always empty.
You can't "Enable" until you fill in the "Bottom Side Replacement". Also, the existing via should be what you're using as non-testpoint vias and the Bottom Side Replacement should be your testpoint via (two different padstacks). Therefore, your row in the bottom section will have two different padstacks listed.
Randy,You're a genious man.I finally got this stupid tespoint add going. It seemed so easy in 15.2 and so complicated in 15.5.1.Thank you again.Mihai