Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
This course combines our Allegro PCB Editor Basic Techniques, followed by Allegro PCB Editor Intermediate Techniques.
Virtuoso Analog Design Environment Verifier 16.7
Learn learn to perform requirements-driven analog verification using the Virtuoso ADE Verifier tool.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
Does anyone know how to change the tolerance '+0.00/-0.00' to text 'SEE BELOW' or something, if the tolerance is 0 in the pad and only display the tolerance if set.
you can change it in MANUFACTURE > NC > DRILL CUSTOMIZATION.
Thanks for your reply,
it's not quite what I was after. What I was trying to say, but I don't think that I explained it very well, is if you are using the tolerance in the .dlt file but is comes out with +0/-0 then I would like it to say something other than +0/-0 i.e. See Below.
I sort of see what you are trying to do but as far as I can tell there is no mechanism to do what you are asking. You can make the tolerance field a USER Defined field, which would force you to specify the tolerance for ever hole size used on the design inside of the default-mil.dlt file, I would not recommend this but it was worth mentioning.The first suggestion to use MANUFACTURE > NC > DRILL CUSTOMIZATION is the easiest and best way to go and you can change all the tolerances that are +0/-0 to your default tolerance. The other added benefit in using the Drill Customization is the tolerances defined in the database will be added to the NCdrill files generated out of Allegro so there is no confusion or conflicting information between the NCdrill data and the NCdrill Legend on your documentation.I guess a good enhancement request would be "Any Padstack with a tolerance defined as +0/-0 should be replaced with a default tolerance specified in the Allegro .brd database" or "The ability to globally replace all the hole sizes with a tolerance of +0/-0 inside of NC Drill Customization with a default tolerance" - Currently the Drill Customization global change applies an updated tolerance across all hole sizes regardless of what they are defined in the library.Hope this helps,Mike CatramboneUTStarcom, Inc.
create a custom padstack. for specific holes with "see text below" create another copy of a 10mil drill and rename it using a 10.01mil drill.Modify your drill table file. Located in your share folder. cadence folder\share\pcb\text\nclegend\default-*.dlt. When you generate nclegend the gui points to this file.open default-mil if your using mils using notepad, make your mods and save in the same folder. create a backup zip just incase it breaks.heres my example:(make__ncTemplate_struct ?Name "custom DRILL CHART by Oscar Miguelino" ?Title "DRILL CHART" ?Units "mils" ?TitleHeight 250 ?TitleTextBlock 9 ?ColumnTitleTextBlock 8 ?DataTextBlock 8 ?PlatingOrder "PlatedFirst" ?ColumnDefinitions '( ("Figure" "FIGURE" 7) ("User" "SIZE" 13) ("User" "TOLERANCE" 14) ("PlateStatus" "PLATED" 10) ("Quantity" "QTY" 6))?CustomData '(( 10.01 "PLATED" "0.010" "+0.0/-0.0 SEE TEXT BELOW" PLATED) ( 10 "NON-PLATED" "0.010" "+/-.003" )( 11.01 "PLATED" "0.011" "+0.0/-0.0 SEE TEXT BELOW" PLATED) ( 11 "NON-PLATED" "0.011" "+/-.003" )))