Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
Dear all,The screen shots shows the ground vias in negative and positive planes of a BGA package. Here some of vias are fully voided due to different net and the antipad of via. But the tool indicates it was connected in negative plane and not connected in positive. I have still doubt that whether it is connected to plane during fabrication in nagetive plane? How can i connect these vias? Is it possible using traces? And which one is best-positive or negative-to set the plane? Seeking correct answer.Thanks,Shiva.
And one more question. What's the differnce between positive and negative plane whether it's power or ground?Thanks.
I feel your better off using positive planes, you can see on the screen what you going to get when you go to gerber / ODB++. The difference between positive plane and negitive plane is in thinking like photographic film. The negitive is the opposite of what the positive (photo) will look like. The signal layers are made as positives.
The isolated connections on negative planes that are formed by the joining of anti-pads was an old problem in Allegro which was corrected some time ago. Basically, a new DRC check was added to check for these island conditions and by default the check is off. Go to Setup > Constraints > Modes and turn on the "Negative plane islands" check so you receive the same results for negative and positive planes.
Hope this helps,
Hello Mike,I have set as you told and got DRC. But my doubt is, how can i connect the seperated or island same net vias? Is it ok as rboquette told, that is set the planes to possitive? In positive planes, it's possible using traces. Please let me know further details.Regards,Shiva.
It is certainly OK to use positive planes instead of negative planes to get the result you are looking for. Negative planes are driven using the anti-pad definition inside of your Via padstacks while positive planes clearances are driven the DRC Clearance to the copper pad by default but you have the option to use the anti-pad to drive positive planes as well.
It most but not all cases the fabrication vendor would like a larger clearance on plane layers to prevent possible plane shorts. This could occur on planes where you have a large mass of copper that tends to shift during processing and also on plated thru hole location which need to be drilled larger to meet the hole size requirements once the holes are plated. I would confirm with the fabrication vendors that you use on what minimum clearance (anti-pad) is required on plane layers and adjust the anti-pad in you padstacks and/or the DRC Clearance to shapes accordingly to avoid any fabrication issues.
You could use positive planes and then add traces to connect all the islands, which would take a lot of your time, but as I said previously it may be in your best interest to consult with your fabrication vendor that your company uses in the hopes that they are OK with reducing the clearance so copper planes can flow the BGA pin fields without being broken up.
Here is a couple images of a small BGA with a slightly modified pin escape to allow the planes to flow to the inner power and ground vias. This can also be a solution to your plane break-up problem you are seeing. It is best to plan ahead during the beginning stages in the design on how you are going to get multiple powers planes connected up. I highlighted GND green and the 4 Powers different colors to illustrate what I have done.
Dear Mike, Very thank you for your valuable feed back. As above figure and as you told the prevention of break-up of planes is possible only in large pitch such as 1mm components ( I guess the image is such one). In short pitch BGA's such as 0.65mm, 0.5mm, the prevention of breaking-up of planes is not possible. So i think it's better to use of positive planes in such cases and/or minimum size of via's with minimum size of anti-pad area.And one more thing, i'm impressed from your knowledge, experience and implementation method. I think we are working at same field. So i think we can be good friends. What's your opinion? Please mail my personal id: shivain79_at_aol_dot_in , we can share our personal details.Warm Regards,Shiva.