Cadence® system design and verification solutions, integrated under our Verification Suite, provide the simulation, acceleration, emulation, and management capabilities.
Verification Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
More Support Log In
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technology. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
In APD15.7, we can add a constraint area by creating a shape and attach the property. However, I have no idea how to create a constraint area in APD16.2. Anyone can help..
How to set up a constraint region in 16.2.
Lets say we want to create a spacing region:
Open constraint manager and create a Spacing Rule set for the constraint region.1. Open Constraint Manager on the board file.2. Select Spacing > All Layers worksheet 3. RMB on the Objects and select Create Spacing CSet 4. Type the name of Spacing CSet and change the pin to pin constraints that allowpin to pin spacing for the 'special' component.Now create a region and assign a spacing CSet to the region.1. In Constraint Manager, select Region > All Layers 2. RMB > Create Region 3. Give a name to the region, and select Ok.4. On the Region worksheet, select the region that you just created, and assignthe Spacing CSet that you had created in the previous step. The rules of thespacing CSet are automatically taken over by the Region.Now create a Shape on Constraint Area subclass and assign the region rules to it.1. On Allegro, Select Shape > Polygon or Rectangular.2. In the Options panel on the Right hand side, select the Class as ConstraintRegion > All.3. From the drop down in the options panel, select the Region you had defined inthe previous step.4. Draw the rectangle or polygon around the component.
In reply to Jeff Gallagher:
Thanks alot. It works now.
The procedure above is correct, but there is additional options you may wish to choose.
1. The shape(s) for the Region do not have to be drawn on the All subclass of the Constraint Region class. You may create the shapes on any etch layer, or the special layers of Outer Layers (i.e. Top and Bottom), Inner Signal Layers, or Inner Plane Layers.
2. You do not have to use a Spacing Constraint Set for the Region. You only have to specify the constraints that you need specifically for this region. By only specifying the pin-pin constraints that you need, you'll improve the drc performance and you're constraint methodology will be easier to understand.
3. Regions also support Physical and Same Net Spacing constraints.
4. When creating the shape, you can select a Region name from the "Assign to Region" drop down on the Option panel, or you can type in a new name. Any new name will automatically appear in Constraint Manager in the Physical, Spacing, and Same Net Spacing worksheets.
Also, in case you weren't aware, there is no limit to the number of shapes that can be part of a Constraint Region.
Is this method available in OrCAD PCB Disigner 16.0?
I can't find the Region in the Constraint Manager.
I found the Constraint Region Class though.
I need to specify constraint for specific component, how can I do so? if at all possible?
Thanks in advance,