Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
Verification Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
I've simulated a very simple circuit, as follows.
It has a step-up signal as input. And signal "n2" is interesting.
Simulation results are presented below.
It is obvious that V(n2) goes up to 1V because of the input excitation, and then descends with time.
I think capacitor is ideal. So why can't V(n2) stay at 1V? Is the capacitor not ideal? Does the capacitor model have some leakage current?
Can anyone help me, please? Thanks a lot!
In reply to xxgenerall:
Have you tried a DC simulation and examined the voltage of node n2? I believe the steady-state voltage across n2 is 0 V - not 1V. The initial voltage of 1 V is due to displacement current and the charge is then re-distributed to set the voltage across the capacitor connected to ground to 0.
Put another way, if the rise time of the 2 V signal is very long (dv/dt is about 0), the node voltage at n1 will eventually rise to 2V, but the voltage at n2 will never change from 0.
In reply to smlogan:
The reason for this is that there is no DC path from n1 to ground (it's floating at DC), and so the simulator inserts a gmin resistor to ground. Since the default value of gmin is 1e-12 Siemens (1e12 ohms), you then have a 2 second time constant - if you simulate for 2 seconds you'll see it's down to 0.369mV (i.e. 63% of the way there, what you'd expect after a time constant).
In this trivial circuit, you could set the option gmin to 0 (this is generally not a good idea, as gmin conductances are there to aid convergence - having absolutely no path to ground means that there are an infinite number of solutions for the DC operating point, since a floating node could be anything; a high value like 1e12 ohms is not unrealistic in terms of leakage).
In reply to Andrew Beckett:
Hi all, I appreciate your help. Thank you very much. ^_^