Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
I am trying to run the PSS+Pnoise to get the linewidth of the VCO.I have set the Pnoise option "augmented=yes" for PSS+Pnoise oscillator simulations.Nevertheless, I cannot get the Lorentzian plot, the phase noise still goes up and becomes larger than 0 dBc at low frequencies.The logfile says:"Compute Floquet mode for autonomous ciruits... ...". It seems the simulator does not use frequency-aware PPV method.
Is there anything wrong in my setting?By the way, the MMSIM version I use is 7.2ISR7
The augmented parameter really has nothing to do with producing a Lorentzian plot. It is to enable an improvement in the PPV method to handle long time constants (often in the bias circuitry) which result in a hump in the phase noise transfer function. In fact from MMSIM72 ISR3 onwards augmented=yes by default in both shooting and HB pnoise.
In earlier versions, when augmented=yes was turned on, it also enabled (for HB only) the calculation of the "line width" and computation of the Lorentzian (i.e. nonlinear) noise shape near the carrier. This was misleading because it was independent of the augmented algorithm, and also was doing it only for HB and not for shooting.
What we did from MMSIM72 ISR4 onwards was to introduce a new parameter "lorentzian" on pnoise and hbnoise:
43 lorentzian=cornerfreqonly This option determines if the Lorentzian plot is used in the oscillator noise analysis. Possible values are no, cornerfreqonly or yes.
The default is just to compute the corner frequency (i.e. the line width), and to get the Lorentzian shape curve you need to set it to "yes".
In reply to Andrew Beckett:
Thank you very much for your response, but I cannot find the parameter "lorentzian" on pnoise and hbnoise.Is it a check box or I have to type it in the additional parameter?Besides, I saw a message in the output log file saying "pnoise 'lorentzain' is not a valid parameter for an instance of 'pnoise'. Ignored"What does it mean?However, after I run the pnosie simulation, the simulation result still shows the line width.I am very confused why it can still compute the line width and if it is a correct result.
In reply to ycyang:
Recent enough versions of the ADE environment would show lorentzian on the options form. In older versions you would just need to type:
in the "Additional Parameters" field on the pnoise/hbnoise options form.
Given the message you described had a typo in it, I don't know what exactly you tried - maybe if this doesn't work you can post both the analysis statements (cut and pasted, rather than transcribed) and the complete spectre.out file (as an attachment; go to the Options Tab when you reply to the post).
Thanks again for your help.I did check the option tab but cannot find "Lorentzian", so I just type "lorentzian=yes" in the Addtional Parameters field.The attched file is the spectre.out file which still shows 'lorentzian' is not a valid parameter for an instance of 'pnoise'. Ignored"Even though, the simulated phase noise has a Lorentzian noise shape near the carrier (I do not know how to insert image yet and cannot post it). Thus I wonder if the result is correct or not.Regards,
Looking at the log file, I see you're using MMSIM 18.104.22.168 . That is the base version of MMSIM72 and is not ISR7 that you mentioned earlier. That is before the ISR4 version I mentioned earlier. Before we introduced the lorentzian parameter, when augmented was yes (which was not "yes" by default before ISR3, although the augmented algorithm was enabled always for HB), it also plotted with the Lorentzian shape. It should be correct.
However, I would probably advise moving to a later version than the one you're using, because at the very least this linkage of the Lorentzian shape with the augmented switch is confusing, to say the least (which is why we sorted it out in ISR4).
I'm a bit confused because initially you said you couldn't get the Lorentzian plot, and now you're saying that you are getting it - and this is nothing to do with the lorentzian parameter you've added, since you're using a version prior to that parameter being supported. I suspect your earlier run was done without augmented being set to yes?
I found I used wrong version of MMSIM after reading your reply. After switching to a later version, the warning message disappeared.As for the problem that I could not get the Loretzain plot in the beginning, I am sure that the option "augmented" was set to yes. I don't know why the Lorentzain didn't show. I will discuss this with our CAD engineer.Thank you very much for you assistance.