Cadence® system design and verification solutions, integrated under our Verification Suite, provide the simulation, acceleration, emulation, and management capabilities.
Verification Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
More Support Log In
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technology. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
I want to know how to write a ocean script that can create a file to display all MOS' region,but I don't know the function.
How to know that where are All MOS in ??
If you mean that you need to determine a region which each MOS in after some simulation, I'm affraid there is no one function to do this and you'll have to read skill docs to obtain a methodology.
If you are talking about values of the CDF description of each MOS (some CDF descriptions have the "reagion" parameter) I think "dbGet" function coul help you.
In reply to VKhlyupin:
If you're using OCEAN, and you've run a DC operating point simulation, then you can use the report() function to do this.
analysis('dc ?saveOppoint t)run()selectResult('dcOpInfo)report(?param "region")
You'll get the region of each device returned as a number. If you look at "spectre -h modelType" - e.g. "spectre -h bsim4" you get:
1 region=triode Estimated operating region. Spectre outputs the number (0-4) in a rawfile. Possible values are off, triode, sat, subth, and breakdown.
and for "spectre -h bjt" you get:
3 region=fwd Estimated operating region. Spectre outputs number (0-4) in a rawfile. Possible values are off, fwd, rev, sat, and breakdown.
So the numbers correspond to the various regions. So for a MOS, 2 means it is in the saturation region.
The previous reply talking about CDF parameters is not relevant - that was (presumably) talking about the instance parameter region - which is merely a hint to the simulator as to which region the device is in, to help with DC convergence (an option that is rarely set, because it's not that practical to set it on each transistor, and anyway it's not the final region - just a clue to the simulator to tell it (say) that the device is off and hence to expect it to be off when trying to reach DC convergence).
In reply to Andrew Beckett:
Thank you,the results are displayed in terminal using your function .But I want to save the results into a text file,can you give me some suggestions?
Can i use such a way to write the results into a text file?
Thank you very much!
In reply to MOSMOS:
ocean> ocnHelp 'report PROTOTYPE report([?output t_filename | p_port] [?type t_type] [?name t_name] [?param t_param] [?format s_reportStyle] [?maxLineWidth charsPerLine]) => t/nil...
So you can do report(?output "./region.txt" ?param "region") or report(?output p ?param "region")
Is there a way to loop through all the transistors and print their operating points using OCEAN or any other tool? I don't want to type the name of the transistors manually.
In reply to Venkatraman Natarajan:
The OCEAN report() function can do that. See the documentation or just type ocnHelp('report) for more details.
Thanks! It works. Is it possible to do mathematical operations like vgs-vth for all transistors and report it?
If it's possible to do that for specific transistors (for example, transistors that end with "_sat"), it would be great.