Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
System Development Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
This course combines our Allegro PCB Editor Basic Techniques, followed by Allegro PCB Editor Intermediate Techniques.
Virtuoso Analog Design Environment Verifier 16.7
Learn learn to perform requirements-driven analog verification using the Virtuoso ADE Verifier tool.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
I have used rmsNoise command to calculate the total integrated rms noise over the desired band. But recently I am seeing wierd behaviour with this command and it throws me error:
*Error* rms Noise data not available
simulator lang=spectre global 0 include "....../ahdlLib/quantity.spectre" C0 (VOUT VSS) capacitor c=1p R0 (VOUT VSS) resistor r=1M R1 (VOUT VDD) resistor r=1M V4 (VSS 0) vsource dc=0 type=dc V1 (VDD 0) vsource dc=1 type=dc noise (VOUT VSS) noise start=1 stop=1M
The ocean commands:
openResults("psf") selectResults("noise-noise") rmsnoise.sch = rmsNoise( 1 100K )
I am able to use noiseSummary('integrated) successfully.
Any idea what's going wrong.
The rmsNoise() function expects the "runObjFile" to be present, which won't be the case if the simulation was run standalone.
I don't see an enormously good reason for this. In fact even if you use wavescan/viva standalone on the data, it doesn't work - this is because it uses the ADE "VN2" function to retrieve the noise output.
When you did the openResults, you'll have seen a message such as this:
WARNING (OCN-6096): Could not find runObjFile under .../psf. Calculator data access functions will not work.
and this is the reason why. The good news is that this is fixed in IC615 (I just tested it).
As a workaround, you could use:
procedure(CCSrmsNoise(from to @key result) sqrt(integ(clip(getData("out" ?result result) from to)**2)))
In reply to Andrew Beckett: