Cadence® system design and verification solutions, integrated under our Verification Suite, provide the simulation, acceleration, emulation, and management capabilities.
Verification Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
More Support Log In
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technology. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
I would run multiple AC simulations (with Spectre simulator) using an Ocean Script. However I would change for each loop the stimulus file. I don't know how to specify the changing of the name of the stimulus file for each run.
Thanks in advance for your help
simulator('spectre)design(...)analysis('ac ...)foreach(stimFile '("file1.scs" "file2.scs" "file3.scs") stimulusFile(stimFile) run() ; process the results as you wish)
Something like that?
In reply to Andrew Beckett:
In reply to lartola:
for(i 1 1000 stimulusFile(sprintf(nil "stimFile%d.scs" i)) run() ...)
Use something like sprintf() to build the filename as you go along.
i've worked on the ocean script for running multiple AC simulation as you said me.
However I get a problem. Actually the loop works perfectly but the simulator seems don't used the correct stimulus file. If I check the netlist file all of the used stimulus are present but when I check the simulated data something seems wrong.
Actually, the simulator seems add loop after loop each the stimulus files. I Need to perform a reset for each run or something like that ?
Following the current ocean script i'm using:
;------------- Initialization -------------------------------------
simulator( 'spectre )
stimulusFile( ?xlate nil "/*******/spectre/schematic/netlist/_graphical_stimuli.scs")
temp( 23.0 )
TotalRun = 3
;------------- Automatic electrical runs -------------------------
Tempfile1 = outfile( "/************net6_testpostprocess.txt" "w")
Tempfile2 = outfile( "/************net7_testpostprocess.txt" "w")
for(i 1 TotalRun
stimulusFile( ?xlate nil sprintf( nil "/*********Stimulis_test_MUSCA_SETcurrent_SRAM_%d.txt" i))
analysis('tran ?stop "0.055E-6" ?method "trap")
envOption( 'analysisOrder list("tran"))
option( 'temp "23.0" )
selectResult( 'tran )
plot(getData("/I4/A") getData("/net06") getData("/net7") getData("/WL") getData("/BLbarre") getData("/BL"))
ocnPrint( v("/net06") ?output Tempfile1 ?numberNotation 'none ?precision 15 ?width 20)
ocnPrint( v("/net7") ?output Tempfile2 ?numberNotation 'none ?precision 15 ?width 20)
Thanks in advance for your time
The problem is that each time you call stimulusFile() with a different file, it adds to the list of stimulus files. The usual way of solving this with OCEAN is to use the delete() function to reset the particular item (you can delete analyses, saves etc), but unfortunately delete('stimulusFile) hasn't been implemented yet.
This is described in my solution 1026408 on Cadence Online Support. The workaround is to use::
asiSetEnvOptionVal(asiGetCurrentSession() 'stimulusFile list(stimFile))
where stimFile is the file you want to set. This will override any previous stimulus file lists that have been set.