• Skip to main content
  • Skip to search
  • Skip to footer
Cadence Home
  • This search text may be transcribed, used, stored, or accessed by our third-party service providers per our Cookie Policy and Privacy Policy.

  1. Blogs
  2. System, PCB, & Package Design
  3. What's Good About Allegro Via Patterns During Group Routing…
Jerry GenPart
Jerry GenPart

Community Member

Blog Activity
Options
  • Subscribe by email
  • More
  • Cancel
CDNS - RequestDemo

Try Cadence Software for your next design!

Free Trials
PCB
PCB Layout and routing
blind vias
diff pairs
inset vias
global route
Routing
staggered vias
layer stacks
Allegro 16.5
SPB
via rules
PCB Editor
High-Density Interconnect
Layout
via
via patterns
design
vias
"PCB design"
PCB design
SPB16.5
Allegro PCB Editor
differential pairs
group routing
Differential Pair Support
buried vias
HDI
PCB Capture
Allegro

What's Good About Allegro Via Patterns During Group Routing? See for Yourself in 16.5!

30 Apr 2012 • 3 minute read

New to the 16.5 release of Allegro PCB Editor is the ability to establish via patterns during group routing.

Group Routing Review

The Allegro PCB Editor supports interactive group routing. Interactive group routing is the routing of more than one net concurrently. You can use this feature when routing a bus with traces that follow the same path and have common physical and electrical rules. To specify the nets for group routing, select the elements (such as clines, pins, vias, and ratsnests) from which to route either by using the Temp Group option from the add connect pop-up menu, or selecting the elements with a window. Routing proceeds from the selected elements.

Note: You can initiate a route by selecting ratsnest lines provided that you have enabled Ratsnests in the Find Filter. To reduce the incidence of accidental ratsnest selection, the editor ignores the ratsnests if you also select other types of elements.
Note: If you are routing from a component with a complicated pin pattern, route from each pin to a location outside the component area. Then group the routes together (outside the component area) in the order that you want to route them as a group -- that is, organize the routes outside the component area so that the layout editor can order and space them properly.


Read on for more details …


Via Pattern Support

Via pattern support during group routing is available when you are in the add connect command. You can add vias during group routing in both the modes-Alternate mode and Working layer mode. With the Alternate use-model enabled, you can select the via from the Options tab. With the Working Layer use-model enabled, you can pick the target-layer from the Add-Via dialog box. For adding vias in group routing, the same padstack (or via-stack) is used for all selected clines, and is determined by the control-trace. A DRC may appear if a padstack is invalid for one or more of the selected clines.

Adding Via Patterns during Group Routing

Select the add connect command using Route — Connect and create group to add vias. In the following figure four cline segments are selected. The control-trace is shown by the white X:




 
Now select via-pattern from pop-up menu and add the via by double clicking the cline segments. The vias remain in the floating state until one additional click is made. New clines will gather, and then group route continues on the new layer. The via-pattern is created, and all the vias will slide dynamically as a group in the direction of the control-trace. The control-trace via is placed directly along the control-trace cline, with no extra vertices added. Extra vertices are added for the other traces if needed.

Types of Via Patterns

There are six type of via patterns. You can select the via pattern from pop-up menu. The Next Pattern option can be used to cycle to the next via pattern in the list:




The shape of the via-pattern can change depending on which cline is the control-trace. To change the control-trace use the pop-up menu. Taper patterns produces the same result as one of the diagonal patterns if the control-trace is at the either of the end. If the vias are small, and/or the selected clines are already far enough apart, in group routing vias are added in-line, with no extra vertices.

Adding Stacked Blind/Buried Vias During Group Routing

For designs using stacked vias, you can select only those layers that can be reached with a single via-stack. The layers that can only be reached with staggered vias cannot be selected for adding vias in group routing. The example in the following figure shows three via-stacks (labeled "1-3"). You can add stacked vias during group routing by invoking the command once:



 
 
If via-stacking is not allowed on layer three, then in order to add the vias from layers 3-to-6 you need to select add via second time, with layer six as the target layer. You can move vias labeled "3:6" vertically up or down until you click to drop them. To avoid any DRCs with the "1-3" via-stacks the "3:6" vias are placed in staggered form.

Please share your experiences using this new 16.5 capability.

Jerry “GenPart” Grzenia


CDNS - RequestDemo

Have a question? Need more information?

Contact Us

© 2025 Cadence Design Systems, Inc. All Rights Reserved.

  • Terms of Use
  • Privacy
  • Cookie Policy
  • US Trademarks
  • Do Not Sell or Share My Personal Information