Cadence® system design and verification solutions, integrated under our Verification Suite, provide the simulation, acceleration, emulation, and management capabilities.
Verification Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
More Support Log In
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technology. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
Hi all, I am using Allegro 15.2 and I want to change component reference designator's text size manually but I don't know how to do it. If I try Edit -> Text, all I can do is just changing the text string but I cannot change the size of the text. Can anybody help me with this problem? Thanks.
You've probably found it by now: Edit->Change and then under the options tab you can choose another text size. To edit the text sizes be sure to be in an idle state and then setup->text sizes
Hi damian_s. Do You want change Reference text size? Using>> 1. Menu>>> setup - textsize click 2. text setup window 1> finde designed the text block number text block check by show element 2> using text block change width,height line space,photo width,char space. change value of do you want? 3. color and visibility window 1> all invisible 2> components group change Ref Des section all visible. 4. Menu>> Edit- change click 1>control panel text check of find tab text block change of opinons tab so you want text size of this brd. regard.
Thank you for your reply. I've try it and it works.
In reply to archive:
How to setup the font sizes in Allegro?
Here are a bit more clear instructions:
1. From the menu click SETUP
2. Select Design Parameters...
3. Select the tab "Text"
4. Inside the "Size" box, click on the button Setup Text Sizes [...]
5. A table opens. The header of the table is: Text Blk Width Height Line Space Photo Width Char Space
Text Blk: is the nickname of the font, as you will call it from the Edit ==> Change ==> Text Block
Width: is the width of the font (for example the distance between the branches of a wide letter like capital W at its top, when the stroke has zero thickness -- see later "Photo Width")
Height: is the height of a full size letter (for example W, when the stroke has zero thickness).
Line Space: is the vertical distance between two lines. It is not really used, it is the recommended spacing when you place two text lines one under the other.
Photo Width: this is the thickness of the pen used to draw this fonts (or in gerbers), or sometimes also called stroke thickness. The larger the number the thicker is the pen. You need to use something proportional to make it look good. Using a very thin line will make it hard to read. If you assign ZERO, the PCB fabricator will default them to min width they can process. If you want to have good control, make sure you actually define the a usable value.
Char Space: is the space between two adjacent characters in the same line, for example two letters WW -- the space between the top branches.
1. Example of a good set of Block Settings to ensure a proportional fonts. The units below are um (thousands of a mm). I use um lately since all my boards are metric and really dense, so I do not need to use decimal numbers. For those who can't think in meters: 1mil = 25.4um. Or divide by 25.4 the numbers in the table and you get mils.
The smallest Photo Width used above is 100um (about 4 mils). That is why the smallest fonts (Blk 1) look drawn with a too thick pen.
2. The "fonts" generated by Allegro are not really fonts in the sense of the fonts used in documents. Allegro generates them using polygonal lines because photo plotters historically could only understand such commands. Unfortunately, when you generate PDF documents from Allegro screens, the text will not be real text and you will not be able to search for it, unless you work hard to pass it through an OCR.
Hope this helps!