Cadence® system design and verification solutions, integrated under our System Development Suite, provide the simulation, acceleration, emulation, and management capabilities.
Verification Suite Related Products A-Z
Cadence® digital design and signoff solutions provide a fast path to design closure and better predictability, helping you meet your power, performance, and area (PPA) targets.
Full-Flow Digital Solution Related Products A-Z
Cadence® custom, analog, and RF design solutions can help you save time by automating many routine tasks, from block-level and mixed-signal simulation to routing and library characterization.
Overview Related Products A-Z
Driving efficiency and accuracy in advanced packaging, system planning, and multi-fabric interoperability, Cadence® package implementation products deliver the automation and accuracy.
Cadence® PCB design solutions enable shorter, more predictable design cycles with greater integration of component design and system-level simulation for a constraint-driven flow.
An open IP platform for you to customize your app-driven SoC design.
Comprehensive solutions and methodologies.
Helping you meet your broader business goals.
A global customer support infrastructure with around-the-clock help.
24/7 Support - Cadence Online Support
Locate the latest software updates, service request, technical documentation, solutions and more in your personalized environment.
Cadence offers various software services for download. This page describes our offerings, including the Allegro FREE Physical Viewer.
The Cadence Academic Network helps build strong relationships between academia and industry, and promotes the proliferation of leading-edge technologies and methodologies at universities renowned for their engineering and design excellence.
Participate in CDNLive
A huge knowledge exchange platform for academia to network with industry. We are looking for academic speakers to talk about their research to the industry attendees at the Academic Track at CDNLive EMEA and Silicon Valley.
Come & Meet Us @ Events
A huge knowledge exchange platform for academia. We are looking for academic speakers to talk about their research to industry attendees.
Americas University Software Program
Join the 250+ qualified Americas member universities who have already incorporated Cadence EDA software into their classrooms and academic research projects.
EMEA University Software Program
In EMEA, Cadence works with EUROPRACTICE to ensure cost-effective availability of our extensive electronic design automation (EDA) tools for non-commercial activities.
Apply Now For Jobs
If you are a recent college graduate or a student looking for internship. Visit our exclusive job search page for interns and recent college graduate jobs.
Cadence is a Great Place to do great work
Learn more about our internship program and visit our careers page to do meaningful work and make a great impact.
Get the most out of your investment in Cadence technologies through a wide range of training offerings.
Overview All Courses Asia Pacific EMEANorth America
Instructor-led training [ILT] are live classes that are offered in our state-of-the-art classrooms at our worldwide training centers, at your site, or as a Virtual classroom.
Online Training is delivered over the web to let you proceed at your own pace, anytime and anywhere.
Exchange ideas, news, technical information, and best practices.
The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information.
It's not all about the technlogy. Here we exchange ideas on the Cadence Academic Network and other subjects of general interest.
Cadence is a leading provider of system design tools, software, IP, and services.
I want to run a PSS and then do PNOISE of a circuit block which has also an Oscillator in it. The oscillator noisecontribution also I have to take into consideration. Due to some reason, I also don't want ot simulate the ocillator noise separately.
Is it possible to do it in SpectreRF ?
Could anybody please tell how it can be done if it is possible ?
This can be done with hb/hbnoise; it's not possible with PSS, since that requires a single tone only, and the common frequency with a driven signal + oscillator would be chaotic (highly nonlinear). Shooting QPSS also doesn't support it because it would essentially have to start again as it tried to solve for the oscillator frequency.
So we have added it for multi-tone harmonic balance analysis, but it's only been added via the HB analysis form itself. The feature is called "semi-autonomous harmonic balance", and there's an example (if my memory is correct) in the SpectreRF workshop at <MMSIMinstDir>/tools/spectre/examples/SpectreRF_workshop/rfworkshop.tar.Z (there's a database and a PDF inside).
In reply to Andrew Beckett:
Thnaks a lot for your reply.
I want to know whether the hb analysis is suitable for hard-non-linearity( inverter based ) oscillator as compared to a LC based Oscillator.
Could you please reply to my query :- http://www.cadence.com/Community/forums/p/26723/1325269.aspx#1325269 ? It has stopped me for doing pnoise analysis further. I think you may be the most suitable person who can clear the doubts ( though I couldn't get any clear-cut answer by reading the documnets ).
In reply to RFStuff:
Hi RF Stuff...
Regarding: want to know whether hb analysis is suitable for hard-non-linearity (inverter based) oscillator as compared to an LC oscillator.
If you have a semi-autonomous circuit (oscillator with a driven source), you MUST use hb with the semi-autonomous option. Only hb has the semi-autonomous capability. Since the circuit is strongly nonlinear, you will need to increase oversample (4 or higher) and also increase the number of harmonic (as compared to a nearly sinusoidal oscillator).
If this is strictly an oscillator and it is a strongly nonlinear oscillator, then use pss analysis (rather than harmonic balance.).
Please see post: /blogs/rf/archive/2008/09/03/tip-of-the-week-when-to-use-harmonic-balance-engine-vs-shooting-newton-engine.aspx?postID=11093
Customer Support Director - Analog/Mixed-Signal/RF AEs
Cadence Design Systems, Inc.
Is it a good option to go for Transient Noise Analysis ( i.e. direct time domain analysis) in these type of chaotic cases ?
I always say that transient noise is the option of last resort. The only reasons to use it are if the circuit is non-periodic in nature and can't be simulated with a more efficient method (such as semi-autonomous HB as described before) or if you need to be able to see a large signal response to the noise (e.g. the noise is large enough to cause distortion or significant intermodulation).
Transient noise is always a challenge, because you need to have sufficient accuracy to allow the noise (which is small for most circuits) to be observed given the usual dynamic range of transient analysis; low frequency noise needs a long simulation, and high frequency noise needs short time steps. So that's short time steps over a long simulation with high accuracy; that tends to mean long simulation times!
Small signal noise analyses are much more efficient and generally more accurate because you don't lose the noise below the numerical noise floor in the simulator, plus you don't need to run over multiple periods to see the average noise effect. So they're nearly always preferable if you can use them.