• Skip to main content
  • Skip to search
  • Skip to footer
Cadence Home
  • This search text may be transcribed, used, stored, or accessed by our third-party service providers per our Cookie Policy and Privacy Policy.

  1. Community Forums
  2. Allegro X PCB Editor
  3. How to find if Padstack is used or not?

Stats

  • Replies 2
  • Subscribers 158
  • Views 13258
  • Members are here 0
More Content

How to find if Padstack is used or not?

Kirti Sikri
Kirti Sikri over 8 years ago

How to find if the padstack in a design is used or not using Allegro Skill?

Thanks,

Kirti

  • Sign in to reply
  • Cancel
  • DavidJHutchins
    DavidJHutchins over 8 years ago

    Below is a simple skill procedure that counts the padstack usage on symbol definitions & nets, then reports any padstacks that are not used

    procedure(PadStackUsage()
        let((PadTable)
            (PadTable = makeTable("PadTable" nil))
            foreach(pad ((axlDBGetDesign)->padstacks)
                (PadTable[pad->name] = 0)
            )
            foreach(symdef (axlDBGetDesign()->symdefs)
                foreach( pin symdef->pins
                    (PadTable[pin->name] = add1(PadTable[pin->name]))
                )
            )
            foreach(net ((axlDBGetDesign)->nets)
                foreach(branch (net->branches)
                    foreach(child (branch->children)
                        if(((child->objType) == "pin") || ((child->objType) == "via") then
                            (PadTable[child->name] = add1(PadTable[child->name]))
                        )
                    )
                )
            )
            foreach(name PadTable
                when(eq(PadTable[name] 0) axlMsgPut("padstack %s not used" name))
                remove(name PadTable)
            )
        )
    )

    • Cancel
    • Vote Up 0 Vote Down
    • Sign in to reply
    • Cancel
  • Kirti Sikri
    Kirti Sikri over 8 years ago

    Thanks.
    A question why do we have to use symdef->pins and then pins which are on nets?

    I had programmatically created a new padstack(using make_axlPadstack) which is not on net or part of symbol definition.

    Hence this code was not able to find those padstacks.

    I used following code

    ;checks if given incheckPadstackName  is to be checked for usage or all padstacks

    (defun allpadstacks (@optional (incheckPadstackName nil))
    (let (vis_list pin_list padstacklist pad_name noDBId key)
    vis_list = axlVisibleGet()
    axlVisibleDesign(nil)
    axlVisibleLayer("PIN" t)
    axlVisibleLayer("VIA CLASS" t)

    axlClearSelSet()
    axlSetFindFilter(?enabled list("noall" "pins" "vias")
    ?onButtons list("noall" "pins" "vias"))
    axlAddSelectAll()
    pin_list = axlGetSelSet()
    axlVisibleSet(vis_list) ;restore design visibility
    axlVisibleUpdate(t)
    axlClearSelSet()
    padstacklist=makeTable("atable1" nil)

    foreach(pin_db pin_list ;go thru layout pin list


    padstack_db = pin_db->definition ;Extract PadstackID from pinID
    pad_name=padstack_db->name ;Extract Padstack Name from PadstackID
    padstacklist[pad_name]=pad_name ;add to padstacklist table

    );end foreach


    (if incheckPadstackName && !padstacklist[incheckPadstackName] then
    printf("Padstack %L is not used\n" incheckPadstackName)
    else
    allPadstacks=axlDBGetDesign()->padstacks
    allPadstacksNameList=nil

    noDBId=nil
    (foreach curPadstack allPadstacks
    key=curPadstack->name
    if(!padstacklist[key] then
    printf("Adding key to noDBId %L\n" key)
    noDBId=cons(key noDBId)
    )
    )
    )
    );let
    );end of defun allpadstacks

    • Cancel
    • Vote Up 0 Vote Down
    • Sign in to reply
    • Cancel
Cadence Guidelines

Community Guidelines

The Cadence Design Communities support Cadence users and technologists interacting to exchange ideas, news, technical information, and best practices to solve problems and get the most from Cadence technology. The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information. By accessing, contributing, using or downloading any materials from the site, you agree to be bound by the full Community Guidelines.

© 2025 Cadence Design Systems, Inc. All Rights Reserved.

  • Terms of Use
  • Privacy
  • Cookie Policy
  • US Trademarks
  • Do Not Sell or Share My Personal Information