Same net shape to via spacing when a via edge touches the shape: how to set the shape to void the via edge?

Hi.

Normally if the via is of the same net name as a dynamic shape then by default if the shape touches the via it will connect because it is of the same net name. However
you could apply a property to the via so that it will not allow a connection to a shape of the same net name. The result will be that the shape will clear the via.

To do this select a via and right click it and choose properties. Add in the property NO_SHAPE_CONNECT and the shape will completely clear around the via. 

Hello Avant, Did you ever find a solution to this?

No, I did not find a solution. 

Avant, 

I was having the same issue, and my fix was to remove a 'drawing property' called "PAD_SHAPE_TOUCH_CONNECTION". This forced the copper shape to be at least 1/2 covering the via to make a connection. If not 1/2 over the via, the copper shape would void as expected and not leave a sliver. I only found this issue after generating an ODB which actually suppressed the pad leading to a NO CONNECTION in the manufacturing files. 

Edit -> properties -> in find filter scroll down to drawing -> delete "PAD_SHAPE_TOUCH_CONNECTION" property. 

Thanks!

This is exactly what I was looking for.

Typical for Cadence to enable an unwanted feature by default.