OrCAD PCB Editor Post processing

That would be correct,

The Board Geometry Outline on an etch layer would end up as a sliver of etch around the board edge, this would be undesireable.

You can add another film to the output to include the Board Geometry>Outline class / subclass and provide this with the etch data and, indeed, with any other films that you want to output. Since the Board Geometry>Outline has a 0 width, you will need to provide a value for the "Undefined Line Width" for the film.

You might want to clarify with you fabricator, what data he is expecting you to provide.

 Hi, i tried to include the BOARD GEOMETRY/OUTLINE in the top and bottom film and set "undefined line width" to 1 in the artwork control box but when i try to view the gerber, i cant see the board outline. My PCB house told me that they cant see the board outline. 

 Do i need to include another film just for the board outline or can i just add the BOARD GEOMETRY/OUTLINE subclass to the top and bottom film. But i stil cant see the board outline... how should i go about this?

Try making the width bigger. It would depend on your design and artwork units. You say 1. If that is in mils then I would set it to at least 6 mils. A tip might be to create a TOP.art which includes etch/top pin/top via/top. BOTTOM.art which has etch/bottom pin/bottom and via/bottom. CRT.art wihich includes board geometry/outline. You might also need to include a soldermask top and bottom and a silkscreen. Have a look at Kraig Mitzners new book Complete PCB design using Orcad Capture and PCB Editor. Not only does he talk you through the software side. He also explains manufacture, board setup etc.

 Hi Steve,when i created the board outline artwork (film with only the board geometry/outline subclass) and with "undefined line width" set to 10 just to test(my system and output units are in mm), i still cant see the board outline in the gerber viewer.

 Can you take a look at my .brd? I missed out something? Thanks.

This is really strange. The Board outline artwork was being created but it but when you examine the art file it was empty. I managed to cure this by adding a photoplot outline. To do this add rectangle then change the class/subclass to manufacture/photoplot outline and draw the rectangle to enclose your board outline. Then your artworks will be created. I would suggest changing your undefined line width (as you have mm you probably only need 0.5 or 1mm as the thickness).

If anyone has suggestions I'd be interested to see..... I tried increasing page size both in design and artwork, moving origin. Recreating the board outline and the artwork....... The only cure was the photoplot outline.