Concept HDL: pin number visibility, and others

Hi,
You need to run the section command.

Type "sec" in the command console, then left click your component. pin numbers should appear.

Subsequent left clicks with either:
remove & replace pin numbers,
or
step through the available pin numbers for the different sections of the part (in the case where you've drawn a multi-sectioned body, like a single AND gate from a LS00)

I haven't tried this, but if you want to section all bodies on a page, try
find bodies
section x
where x is the name of the group cadence puts the bodies into.


Path is not the refdes, it's a locator used by cadence to identify the body in the schematic. Think of a multi bodied asic. Each body of the ASIC will have a different path, but all bodies will have the same refdes.
$location is the refdes.

To change the body of the cap, try the edit comand, then navigate to and open the cap body. If you are using a common library, don't move the pins - or you will have a bunch of angry engineers beating on your desk (or maybe on you, it depends how much coffee they've had!! :) ), instead, create a new version of the cap.

Quote: "the bigger thing: i have a reference design given in .CSA files, 100 of them. how can I just open them?"

Create a dummy project; all the way to creating a schematic; Save a Page 1

Put all the .CSA files in the SCH folder

They will open. :) These are simply the ASCII formatted files for the schematic pages. This is how I supply updated pages to customers. They simply delete the .csb, css and csp files; and save my new .csa files.

This is also a way to open older version Concept schematics. Newer versions will open older .csa schematic. I used to do this converting UNIX schematics to Windoze. :)

Good day.
Mitch

Hi Mitch,
Reading from your above post, I have a related question that needed help.

I am looking at my design and want to update all the reference designator. For example, like Orcad, I can turn all refdes to ?.
How do I do that in DE HDL? This would be a great help.

Thanks for the above post, its helpful to me as well.

Jason

Use Tools->Global Update->Global Property Change

Ths can be used to change property values across the design, sheet or module - you'll need to change LOCATION and $LOCATION, preserve the source property and reset the value to ?. Make sure that you take a backup - this will affect placement if a brd (PCB) exists.

Hi Andrew,
Thank for your reply, I got your reponse on the other thread.


May I ask where you are based?, I am based in Taiwan.
Just wondering where you are, because it's a strange time for US/Europe to reply at this hour.


Thanks again,
Jason Huang