How to insert file containing Design Variables in Analog Design Enviroiment

Your question is rather unclear as to what you actually want to do. Please read the Forum Guidelines.

Andrew.

 I didn't found any document in google and in this forum.

I have 24 variable calculated with matlab.... for example Vo1, Vo1, Vo3, ...Vo24. And I have 100 ideal voltage source in cadence schematic.

I wolud like to set the value of DC voltage for every voltage source at value Vo1...Vo24.... Then in the analog enviroiment I would like to import a text file created with Matlab. the contenent of this file is similar

Vo1 3.3

 Vo2 0

..

..

..

Vo24 3.3

My scope is to import aDesign Variable from text file.

 Somebody Can help me.

 This time the question is clear? I need help because I don't find an appropriate documentation...

Please remember that these forums are community forums, in which volunteers (including folks from Cadence) respond in their spare time. If you needed an urgent answer, you should go to Customer Support.

Your question was clear. The following SKILL code can be used:

 procedure(abImportDesignVars(fileName  
    @optional (session asiGetCurrentSession()) "tg")
  let((prt data designVars)
    prt=infile(fileName)
    unless(prt
      error("Cannot read design variable file %s\n" fileName)
    )
    while(gets(data prt)
      data=parseString(data)
      when(listp(data) && length(data)>=2
    designVars=tconc(designVars data)
      )
    )
    close(prt)
    asiSetDesignVarList(session car(designVars))
  )
)

This can be pasted in the CIW, or stored in a file, and then loaded using:

load("/path/to/abImportDesignVars.il")

Then, with the ADE session as the current window (make sure you've interacted with it somehow to make it current), use:

abImportDesignVars("/path/to/your/designVars.txt")

and it should then import the variables into ADE.

Regards,

Andrew.

 Hi Andrew,

 Can you post an example of a text file? Specifically, what would the format of the text file be for five capacitors {C1,C2,C3,C4,C5} whose value I'm importing.

 Best,

Nick 

Nick,

Assuming you have design variables for those capacitors, where the variables are called C1, C2 etc, then the file would contain:

C1 1.2p
C2 3p
C3 0.9p
C4 10p
C5 3.14p

or whatever.

Regards,

Andrew.

Hi Andrew, I came across to this useful post and I've tried to use the procedure but I get the following error:

*Error* asiSedDisgnVarList: no applicable method for the class - list

My designVars.txt file is a simple 3 raws:

a 1

b 2

c 3

prior to issue the command I selected the ADE windows and I' am using cadence icfb 5.10. Any idea what's wrong? 

Thanks a lot

This happens if the Analog Design Environment window is not the current window. To make sure of that, first select a menu in the ADE window (e.g. Setup->Design and then cancel the form). The bar above the menus should go a dark grey/blue colour when it's current. 

I've just tested it in IC5141 and I see the error if the schematic window is current, but if the ADE window is current then it works with no error.

Regards,

Andrew.

thanks Andrew it works like a charm!