Stats

  • Locked Locked
  • Replies 6
  • Subscribers 128
  • Views 16980
  • Members are here 0
This discussion has been locked.
You can no longer post new replies to this discussion. If you have a question you can start a new discussion

Ultrasim: individual accuracy setting on subcircuit level ?

baenischfau

Hi all,

 

I'm currently simulating a big mixed signal block, consisting of two big blocks. The instance block I0 is

pure digital logic, instance I1 is mainly analog but also includes some digital parts. I'm using Ultrasim

for verification but due to the analog parts I'm forced to use a quite strict accuracy setting to get the

results about right. However this setting is killing the digital part ...

 

I know that some other simulators offer the possibility to define accuracy levels for each instance in

a design, e.g. set I0 to Digital Fast and I1 to Analog. Is something like this possible with Ultrasim ?

 

Best Regards

 

Andi

Parents
  • Andrew Beckett

    Andi,

    This can be done in the hierarchy editor. Create a config view (File->New->CellView and pick your lib cell view and set the Type to be "config". Then when this opens, hit Use Template and pick "spectre". Make sure that the top cellView is pointing to your schematic and OK that form.

    You'll then get a Table view showing Cell Bindings and a Tree View showing instance bindings - this is how you control which views are used for each cell or instance with greater control than just a view list and stop list which is applied everywhere.

    For Ultrasim usage, use View->Properties. You'll see some additional columns appear in the table and tree view, including sim_mode and speed. You can click on these for a particular cell, or a particular instance. sim_mode is a cyclic with the various sim_mod choices (e.g.  s, a, ms, da, df, dx) - and you can also set the speed.

    Save your setup, and then you can hit the Open button in the hierarchy editor to open the configured schematic, From here, launch ADE (you'll see ADE shows the config as being the view being simulated) and then if Ultrasim is the simulator, it will take this information and add it to the netlist so that Ultrasim knows the per-cell or per-instance mode and speed settings.

    Hope that helps,

    Regards,

    Andrew.

Reply
  • Andrew Beckett

    Andi,

    This can be done in the hierarchy editor. Create a config view (File->New->CellView and pick your lib cell view and set the Type to be "config". Then when this opens, hit Use Template and pick "spectre". Make sure that the top cellView is pointing to your schematic and OK that form.

    You'll then get a Table view showing Cell Bindings and a Tree View showing instance bindings - this is how you control which views are used for each cell or instance with greater control than just a view list and stop list which is applied everywhere.

    For Ultrasim usage, use View->Properties. You'll see some additional columns appear in the table and tree view, including sim_mode and speed. You can click on these for a particular cell, or a particular instance. sim_mode is a cyclic with the various sim_mod choices (e.g.  s, a, ms, da, df, dx) - and you can also set the speed.

    Save your setup, and then you can hit the Open button in the hierarchy editor to open the configured schematic, From here, launch ADE (you'll see ADE shows the config as being the view being simulated) and then if Ultrasim is the simulator, it will take this information and add it to the netlist so that Ultrasim knows the per-cell or per-instance mode and speed settings.

    Hope that helps,

    Regards,

    Andrew.

Children
No Data

Community Guidelines

The Cadence Design Communities support Cadence users and technologists interacting to exchange ideas, news, technical information, and best practices to solve problems and get the most from Cadence technology. The community is open to everyone, and to provide the most value, we require participants to follow our Community Guidelines that facilitate a quality exchange of ideas and information. By accessing, contributing, using or downloading any materials from the site, you agree to be bound by the full Community Guidelines.