DRC from TCL

Go to Options >Extended Preferences > Command Shell > Enable Journaling

After this is done, any task done in Capture will result in the corresponding TCL command to be printed in the Capture TCL window.

You can save these commands and rerun these any number of times. For example, to run a DRC the command is:

​Menu "Tools::Design Rules Check" | DialogBox  "OK" "C:/Users/bforsse/AppData/Local/Temp/CAPTURELOG/Wed_Mar_08_10_52_08_2017/Design Rules Options_1.xml"

Save the xml file that is created (for example, F:/temp/drc/ Design Rules Options_1.xml).

Run the DRC command by typing it in the Capture Tcl window as follows:

Menu "Tools::Design Rules Check" | DialogBox  "OK" <xml file path>

Example:

Menu "Tools::Design Rules Check" | DialogBox  "OK" “F:/temp/drc/ Design Rules Options_1.xml”).

Hope this helps!

Thanks for your message.

Which version are you using? I am on 22.1 and I had the Journaling already enabled. There I can only see 

Menu "Tools::Design Rules Check"

There is no path given to this command. 

HI Georg,

Please try the below tcl command , which dump the drc rule in drc.log file and then use drc.log to run the drc.

RECORD:

1. Type following command in capture command console:

orPrmAutomation::setMode 1
orPrmAutomation::setPath {D:/temp/drc.log}

2. Launch DesignRuleCheck UI , select the DRC rules you want to configure and press Run. This will create a file at the above path.

REPLAY:

3.Type following command in capture command console:

orPrmAutomation::setMode 2
orPrmAutomation::setPath {D:/temp/drc.log}
Menu "PCB::Design Rules Check" | DialogBox "OK" "C:%temp%/CAPTURELOG/<Folder_name_with_day_date>/Undo Warning!!_1.xml"

Hope this helps!

Hi CadAP, 

I am still having problems executing the DRC check automatically. 

2. 

I tried your suggested way, but in the command window following gets printed after I ran the DRC manually:

Error : invalid command name "OnScriptExecComplete"

The drc.log file is still generated.

3. 

I did not "pipe" the DialogBox stuff, because it does not get displayed in my command window, when I execute the DRC manually even though the logging is enabled. has this maybe changed in OrCAD 22.1 and you are using 17.4? 

Using just the command 'Menu "PCB::Design Rules Check" ' starts the DRC then automatically, but I get following printed on the command window.

     Menu "PCB::Design Rules Check"Error reading XML data.Error reading XML data.

When I use 'Menu "PCB::Design Rules Check" | DialogBox "OK" "C:/temp/Undo Warning!!_1.xml" ', then the DRC window just opens, but it does not start automatically and after running it manually then I get the same "Error reading XML data" again.

Any other hints?

Hi George,

Please remove the below dirtive form the capture.ini if present.

IssueUndoWarning=FALSE

After removing you can run the step 2.

2. Launch DesignRuleCheck UI , select the DRC rules you want to configure and press Run. This will create a file at the above path.

Then try rest fo the steps.

Make sure that drc.log file and undo Warning!!_1.xml file location are correct.

It runs on SPB22.1 also.