How transient operating point is calculated in cadence

 Hi prashu,

    have you solved your problem? it seems that a dc analysis should be excuated before the transient analysis. and the transient operation point should be a fixed point, the same meaning with the DC point. i don't know how to observe the operation region during the simulation either, but i suggest you to annotate the transient node voltage, and you can calculate it by hand. any way, you can know the transistor operation mode by this way, i hope this will be helpful.

regards,

zfeng

Normally the transient operating point is showing you the final operating point at the end of the simulation - this is if you have "Save Final Op Pt" enabled on the Transient Options Form.

Additionally you can fill in "infotimes" on the Transient Options form to say which times you want it to output a full operating point. If you do this, you'll then get a choice when you annotate the transient operating points as to which one you wish to annotate.

Regards,

Andrew.

 Hi,

    yes, what andrew has said is right, you can set some "time info" in the option form. by the way, i notice there is also a "captab" option, can i save the "capinfo" -capacitance of any node into a file? if not, how can i monitor a node capacitance changes versus time?

regards,

zfeng

Zfeng,

Spectre itself can do this - you would specify the infoname parameter on the tran analysis to whatever you've called the info analysis with what=captab. However, support for doing this through ADE is limited. You can do this:

1. Enable captab on your DC analysis
2. On the transient analysis, fill in the Additional Parameters field on the options form to be:
   infoname="capInfo_dc" infotimes=[1n 2n]
3. Don't fill in the infotimes field (actually you can, but then you get a potential conflict as there will be two infoname parameters on the tran analysis line, so probably not a good idea, and then the results post-processing doesn't work).

Interestly you can then use Results->Print Capacitance Table and choose which time to show. You can also access the data in the results browser and plot the capacitances versus the times specified in the infotimes.

Regards,

Andrew.

Hello, Andrew.

 I followed above steps you talked and it woks fine at the firtst time.

 It failed when I tried to do another other simulation. The error message

shows the following

Warning from spectre at time= 10us during transient analysis 'tran'

Warning: The analysis 'info-captab'  is not supported in infoname in this mode.

Hope you can give me something to fix it.

Regards,

Richard

Richard,

I've reproduced the problem - it's there in MMSIM11.1 too. I suspect it's an oversight, so I've filed CCR  972106 to address this.

If  you want visibility of the CCR and when this will be fixed, you should log a service request with customer support for this issue, and then the AE can file a duplicate of that CCR (please reference this discussion on the forum).

Regards,

Andrew.